Creating Points
Creating Points
Objectives
Create points.
Create points using coordinates.
Create equidistant points.
Create intersection points.
Create projection points.
Video link :- Creating Points
Prerequisites
The Sketch tools toolbar must be visible, and Dimensional and Geometrical constraints should be activated.
All SmartPick options must be active.
Make sure to be working in Millimeters for this lesson. Go to ME > Preferences.
In the Preferences dialog go to General > Parameters and Measure, under the Units tab and select Length and click the drop down menu to select Millimeter (mm) as shown in the image below.
Create a Point by Clicking
Step 1:
Create a new 3D part. Select the Model section of the action bar and click on Positioned Sketch.
Step 2:
The Sketch Positioning dialog appears. For Planar Support the Type is set to Positioned and the Reference is YZ Plane. For this lesson leave all other boxes as shown.
You can select the plane by clicking on the yz plane in the tree.
Or you can move the cursor over the yz plane in the Graphics Window, the selected plane will show in the Reference box.
Step 3:
Make sure Dimensional and Geometrical constraints are activated under the Sketch section in the action toolbar as shown in the image below.
Step 4:
Next select Point By Clicking (also known as Point) under the Sketch section in the action toolbar.
If the Point By Clicking command is not shown select the small arrow directly next to the current point command and a menu will appear with the selection of other Point commands to choose from, as shown below.
Step 5:
Select any location for the point by picking in the Graphics Window to create a point. You have created a Point. The dimensional and geometric constraints will not appear.
Step 6:
In order for the dimensional and geometric constraints to appear along with creating a point, select Point By Clicking again, the Tools Palette dialog appears. In the Tools Palette dialog enter a value of 130 mm for H. Press the Tab button on the keyboard to move to the V coordinate and place a value of 45 mm in the box. Press Enter to place the point and the dimensional and geometric constraints will then appear, as shown in the image below.
Step 7:
You have now created a Point.
Step 8:
Leave this sketch open and use it to continue to the next lesson below.
Step 9:
At any point within this exercise you may exit the sketch by selecting the Exit App.
To get back into the sketch simply double click Sketch under Part Body in the Specification Tree to open the sketch.
Step 10:
To Save your 3D Part first properly name it by making sure you are out of the Sketch and in the Specification Tree go to the top and right click on Physical Product. A pop up menu appears, select Properties.
Step 11:
A Properties dialog box appears. Under the Reference tab place a name in the open Title box as shown in the image below. When finished select OK.
Notice the name change within the Tab and 3D Part.
Step 12:
Next got to the Share button to the right of the Top Bar and click Save to save your part within the Enovia PDM database.
Please see your Enovia PDM system administrator to make sure you have the proper authorization and place to save your part within the database.
Creating Points Using Coordinates
Step 1:
Continue using the sketch you created previously and throughout this exercise. Under the Sketch section select Point By Using Coordinates . If the Point By Using Coordinates command is not shown select the small arrow directly next to the current point command and a menu will appear with the selection of other Point commands to choose from, as shown below.
The Point Definition dialog displays.
Step 2:
Enter the coordinates of the point. Select the Cartesian tab and set the H coordinate value to 60 mm then set the V coordinate value to -35 mm.
You can also place Polar coordinates as well by selecting the Polar tab.
Step 3:
Click OK to create the point and its associated dimensions.
Step 4:
Leave this sketch open and use it to continue to the next lesson below.
Creating Equidistant Points- Points and Length
Step 1:
In order to show how equidistant points command works you will need to create a line in this lesson.Under the Sketch section select Line and click in the Graphics Window to create a straight line as shown in the image below.
Step 2:
In the Graphics Window, select the line you just created.
Then select Equidistant Points command under the Sketch Section.
If the Equidistant Points command is not shown select the small arrow directly next to the current point command and a menu will appear with the selection of other Point commands to choose from, as shown below.
Step 3:
The Equidistant Point Definition dialog displays.
Step 4:
For this lesson we will use Points & Length in the Parameters drop down menu. In the New Points text box, enter 7.
Step 5:
Click OK to create the points. Notice how the points are created equally spaced along the line with their geometric and dimensional constraints.
Step 6:
Leave this sketch open and use it to continue to the next lesson below.
Creating Equidistant Points- Points and Spacing
Step 1:
Under the Sketch section, deactivate Dimensional Constraint.
Step 2:
For this lesson you will need to create an Arc. Under the Sketch section select Arc as shown in the image below.
Select anywhere in the Graphic Window and you will start by creating a center of a circle. Next drag the center point to the right as shown in the image below.
Step 3:
Next click the left mouse button to then drag the point up and over to the left and when the cursor is at the opposite end of the first arc point created, click the left mouse button to finish the arc, as shown in the images below.
Step 4:
Now that the Arc is created, select the Equidistant Point command under the Sketch section. In the Graphics Window, pick the arc as the element on which you want to create the points. Then under the Sketch section select Equidistant Point Definition and the dialog displays.
Step 5:
Next, pick the left endpoint of the arc shown as the origin point.
Step 6:
If the points appear opposite of the arc click the Reverse Direction button to place the point on to the arc.
Step 7:
In the New Points text box, enter 10 and in the Spacing text box, enter 30.
Step 8:
Click OK to create the points.
Step 9:
Leave this sketch open and use it to continue to the next lesson below.
Creating Equidistant Points – Spacing and Length
Step 1:
For this lesson create another Line as you did in the previous lesson Creating Equidistant Points – Points and Length.
Step 2:
In the Graphics Window select the newly created line. Next select the newly created line, then select Equidistant Points and it's dialog displays. Pick the end point or another point on the geometry you selected. This is where the point spacing will start from. The Parameters drop down menu becomes active.
Step 3:
In the Parameter drop down menu, select Spacing and Length.
Step 4:
In the Spacing text box, enter the spacing.
Step 5:
In the Length text box, enter the length.
Step 6:
Click OK to create the points and dimensions.
Step 7:
Leave this sketch open and use it to continue to the next lesson below.
Creating Intersection Points
Step 1:
Before beginning the next make sure Dimensional and Geometrical constraints are activated under the Sketch section in the action toolbar as shown in the image below.
Step 2:
In order to show how the intersection point command works you will need to create two intersecting lines in this lesson. Under the Sketch section select Line and click in the Graphics Window to create the first line at a slight angle, as shown in the images below.
Select the Line command again and create a second line that intersects the first line as shown in the image below.
Step 3:
Select Intersection Point under the Sketch section.
Step 4:
In the Graphics Window, pick the first line to intersect.
Then select the second line.
Step 5:
Notice that the intersection point and geometric constraint are created where the two lines intersect.
Step 6:
Leave this sketch open and use it to continue to the next lesson below.
Creating Projection Points
Step 1:
In order to show how the projection point command works you will need to create a line and 5 points in this lesson.
Under the Sketch section select Line and click in the Graphics Window to create a line at an angle, as shown in the images below.
Step 2:
Next create 5 points by going to Point By Clicking and placing the points as shown in the images below.
Double click on the Point icon to keep the Point By Clicking command, this will keep you from having to select the Point icon every time you need to make a point.
Place the points under the Line staggered as shown in the image below.
Step 3:
In the Graphics Window, select the five points for projection. To do this click and hold the left mouse button and drag a box around the five points to select them all at once, as shown in the image below. The points will become highlighted.
Step 4:
Next select the Projection Point command under the Sketch section.
Step 5:
The Tools Palette dialog appears, make sure the Orthogonal Projection is selected, as shown in the image below. Then pick the line as the element for the points to project onto.
The points and geometric constraints are projected onto the line.
Step 6:
Leave this sketch open and use it to continue to the next lesson below.
Align Points
Step 1:
In order to show how the align points command works, you will again need to create 5 points and a line the same way as you did in the previous lesson.
Step 2:
Begin creating 5 points by going to Point By Clicking and placing the points as shown in the images below.
Double click on the Point icon to keep the Point By Clicking command, this will keep you from having to select the Point icon every time you need to make a point.
Slightly stagger the points as shown in the image below.
Step 3:
In the Graphics Window, select the five points to align. To do this click and hold the left mouse button and drag a box around the five points to select them all at once, as shown in the image below. The points will become highlighted.
Step 4:
With the points highlighted, select the Align Points command under the Sketch section.
The Tools Palette dialog appears. Make sure the Along a Direction option is selected and move the cursor to any direction you choose.
You can also place specific values within the Direction and Angle boxes to place points in any direction.
Step 5:
Click the left mouse button and notice how the points are all aligned and geometrically constrained to the direction you chose.
Step 6:
Next, to use the same points with the other options in the Align Points command simply press the CTRL and Z buttons together on your computer keyboard to back out of the previous command. Only press the CTRL and Z buttons once so the 5 points are highlighted and back in the staggered position, as shown in the image below.
Step 7:
With the 5 staggered points highlighted, select the Align Points command under the Sketch section.
In the Tools Pallette select the Horizontal Alignment option and click in the Graphics Window.
You can also place specific values within the Direction and Angle boxes to place points in any direction.
Step 8:
Notice how the 5 points are now geometrically constrained to a horizontal position.
Step 9:
Once again press the CTRL and Z keyboard buttons to back out of the last command in order to do the next option in Align Points command.
Step 10:
With the 5 staggered points highlighted, select the Align Points command under the Sketch section. In the Tools Pallette select the Vertical Alignment option and click in the Graphics Window.
You can also place specific values within the Direction and Angle boxes to place points in any direction.
Step 11:
Notice how the 5 points are now geometrically constrained to a vertical position.
Step 12:
Once again press the CTRL and Z keyboard buttons to back out of the last command in order to do the next option in Align Points command.
Step 13:
With the 5 staggered points highlighted, select the Align Points command under the Sketch section. In the Tools Pallette select the Change Origin Point option and click in the Graphics Window.
Step 14:
The Change Origin Point command allows you to select any of the other points as an origin and then gives you a second option of selecting different directions to align the points highlighted. Begin by selecting a point as shown in the image below.
Step 15:
Select the alignment direction of your choice and then move the cursor in the Graphic Window.
Notice how the 5 staggered points are now aligned in the option selected.
Step 16:
Once again press the CTRL and Z keyboard buttons to back out of the last command in order to perform the final option in Align Points command. You will need to create a Line at an angle just above the 5 staggered points.
Step 17:
Create a Line by selecting Line command under the Sketch section and click in the Graphics Window to create the line at an angle, as shown in the images below.
Step 18:
In the Graphics Window, select the five points to align. To do this click and hold the left mouse button and drag a box around the five points to select them all at once, as shown in the image below. The points will become highlighted.
Step 19:
With the 5 staggered points highlighted, select the Align Points command under the Sketch section. In the Tools Pallette select Align Along Selected Linear Element option.
Step 20:
Select the line you just created.
Step 21:
Notice how the 5 staggered points are now aligned and geometrically constrained to the line you just created.
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